The high frequency and large switching currents of the LP87332D make the choice of layout important. Good power supply results only occur when care is given to proper design and layout. Layout affects noise pickup and generation and can cause a good design to perform with less-than-expected results. With a range of output currents from milliamps to several amps, good power supply layout is much more difficult than most general PCB design. Use the following steps as a reference to ensure the device is stable and maintains proper voltage and current regulation across its intended operating voltage and current range.
- Place CIN as close as possible to the VIN_Bx pin and the PGND_Bx pin. Route the VIN trace wide and thick to avoid IR drops. The trace between the positive node of the input capacitor and the VIN_Bx pins of LP87332D, as well as the trace between the negative node of the input capacitor and the power PGND_Bx pins, must be kept as short as possible. The input capacitance provides a low-impedance voltage source for the switching converter. The inductance of the connection is the most important parameter of a local decoupling capacitor — parasitic inductance on these traces must be kept as small as possible for proper device operation. The parasitic inductance can be reduced by using a ground plane as close as possible to the top layer by using thin dielectric layer between the top layer and the ground plane.
- The output filter, consisting of L and COUT, converts the switching signal at SW_Bx to the noiseless output voltage. The output filter must be placed as close as possible to the device, keeping the switch node small for best EMI behavior. Route the traces between the output capacitors of the LP87332D and the input capacitors of the load direct and wide to avoid losses due to the IR drop.
- Input for analog blocks (VANA and AGND) must be isolated from noisy signals. Connect VANA directly to a quiet system voltage node and AGND to a quiet ground point where no IR drop occurs. Place the decoupling capacitor as close as possible to the VANA pin.
- If remote voltage sensing can be used for the
load, connect the LP87332D feedback pins FB_Bx to the respective
sense pins on the load capacitor. The sense lines are susceptible to noise. They
must be kept away from noisy signals such as PGND_Bx, VIN_Bx, and SW_Bx, as well
as high bandwidth signals such as the I2C. Avoid both capacitive and
inductive coupling by keeping the sense lines short and direct, and close to
each other. Run the lines in a quiet layer. Isolate them from noisy signals by a
voltage or ground plane if possible. If series resistors are used for load
current measurement, place them after connection of the voltage feedback.
- PGND_Bx, VIN_Bx and SW_Bx must be routed on thick layers. They must not surround inner signal layers which are not able to withstand interference from noisy PGND_Bx, VIN_Bx and SW_Bx.
- LDO performance (PSRR, noise, and transient response) depend on the layout of the PCB. Best performance is achieved by placing CIN and COUT as close to the LP87332D device as practical. The ground connections for CIN and COUT must be back to the LP87332D AGND with as wide and as short of a copper trace as is practical and with multiple vias if routing is done on other layer. Avoid connections using long trace lengths, narrow trace widths, or connection through small via. These add parasitic inductances and resistance that results in inferior performance, especially during transient conditions.
Due to the small package of this converter and the overall small solution size, the thermal performance of the PCB layout is important. Many system-dependent issues such as thermal coupling, airflow, added heat sinks and convection surfaces, and the presence of other heat-generating components affect the power dissipation limits of a given component. Proper PCB layout, focusing on thermal performance, results in lower die temperatures. Wide power traces can sink dissipated heat. This can be improved further on multi-layer PCB designs with vias to different planes. This results in reduced junction-to-ambient (RθJA) and junction-to-board (RθJB) thermal resistances, thereby reducing the device junction temperature, TJ. TI strongly recommends performance of a careful system-level 2D or full 3D dynamic thermal analysis at the beginning product design process by using a thermal modeling analysis software.